PRNSOL, Item, Comp
Prints nodal solution results.
ItemLabel identifying the item. Valid item labels are shown in th etgable below. Some items also require a component label.
CompComponent of the item (if required). Valid component labels are shown in the table below. Default = COMP.
Prints the nodal solution results for the selected nodes in the sorted sequence.
For example, PRNSOL,U,X prints the X component of displacement vector U (that is, the UX degree of freedom).
Component results are in the global Cartesian coordinate directions unless transformed (RSYS).
Various element results also depend upon the recalculation method and the selected results location (AVPRIN, RSYS, LAYER, SHELL, and NSEL).
If LAYER is issued, the resulting output is listed in full graphics mode (/GRAPHICS,FULL).
You can define which component of the nodal load (static, damping, inertia, or total) should be used (FORCE).
PowerGraphics can affect your nodal solution listings. For PowerGraphics (/GRAPHICS,POWER), results are listed for the model exterior surfaces only.
When shell element types are present, results are output on a surface-by-surface basis. For shell elements (such as SHELL181 or SHELL281), and for ELBOW290, printed output is for both the top and bottom surfaces. For solid elements such as SOLID185, the output is averaged for each surface and printed as follows:
Node at a vertex: Three lines are output (one printed line for each surface).
Node on an edge: Two lines are output (one printed line for each surface).
Nodes on a face: One value is output.
Nodes interior to the volume: No printed values are output.
If a node is common to more than one element, or if a geometric discontinuity exists, several conflicting listings may result. For example, a corner node incorporating results from solid elements and shell elements could yield as many as nine different results; the printed output would be averages at the top and bottom for the three shell surfaces plus averages at the three surfaces for the solid, for a total of nine lines of output. The program does not average result listings across geometric discontinuities when shell element types are present. It is important to analyze the listings at discontinuities to ascertain the significance of each set of data.
The printed output for full graphics (/GRAPHICS,FULL) averages results at the node. For shell elements, the default for display is TOP so that the results for the top of the shell are averaged with the other elements attached to that node.
If NSORT, ESORT or /ESHAPE is issued with PowerGraphics enabled (/GRAPHICS,POWER), PRNSOL behaves as though full graphics mode is enabled (/GRAPHICS,FULL).
Items marked [2] are not supported by PowerGraphics.
To print midside nodes, first issue /EFACET,2.
Table 215: PRNSOL - Valid Item and Component Labels
General Item and Component
Labels PRNSOL, Lab, Item, Comp | ||||
|---|---|---|---|---|
| Item | Comp | Description | ||
| Valid item and component labels for nodal degree of freedom results are: | ||||
| U | X, Y, Z | X, Y, or Z structural displacement. | ||
| COMP | X, Y, and Z structural displacements and vector sum. | |||
| ROT | X, Y, Z | X, Y, or Z structural rotation. | ||
| COMP | X, Y, and Z structural rotations and vector sum. | |||
| TEMP [1] | Temperature. | |||
| PRES | Pressure. | |||
| VOLT | Electric potential. | |||
| MAG | Magnetic scalar potential. | |||
| CONC | Concentration. | |||
| V | X, Y, Z |
| ||
| COMP |
| |||
| A | X, Y, Z |
| ||
| COMP |
| |||
| VEL | X, Y, Z | X, Y, or Z velocity in a structural transient dynamic analysis (ANTYPE,TRANS). | ||
| COMP | X, Y, and Z velocity and vector sum in a structural transient dynamic analysis (ANTYPE,TRANS). | |||
| ACC | X, Y, Z | X, Y, or Z acceleration in a structural transient dynamic analysis (ANTYPE,TRANS). | ||
| COMP | X, Y, and Z acceleration and vector sum in a structural transient dynamic analysis (ANTYPE,TRANS). | |||
| OMG | X, Y, Z | X, Y, or Z rotational velocity in a structural transient dynamic analysis (ANTYPE,TRANS). | ||
| COMP | X, Y, and Z rotational velocity and vector sum in a structural transient dynamic analysis (ANTYPE,TRANS). | |||
| DMG | X, Y, Z | X, Y, or Z rotational acceleration in a structural transient dynamic analysis (ANTYPE,TRANS). | ||
| COMP | X, Y, and Z rotational acceleration and vector sum in a structural transient dynamic analysis (ANTYPE,TRANS). | |||
| CURR | Current. | |||
| EMF | Electromotive force drop. | |||
| DOF | All available degree of freedom labels (10 maximum). | |||
| FICT | TEMP | Fictive temperature. | ||
| SPL | Sound pressure level. | |||
| SPLA | A-weighted sound pressure level (dBA). | |||
| VNS | Normal velocity on the structural surface. [6] | |||
| Valid item and component labels for element results are: | ||||
| S | COMP | X, Y, Z, XY, YZ, and XZ component stresses. | ||
| PRIN | S1, S2, S3 principal stresses, SINT stress intensity, and SEQV equivalent stress. | |||
| EPEL | COMP | Component elastic strains. | ||
| PRIN | Principal elastic strains, strain intensity, and equivalent strain. | |||
| FAIL | Maximum Strain Failure Criteria. [2][4] | |||
| EPTH | COMP | Component thermal strains. | ||
| PRIN | Principal thermal strains, strain intensity, and equivalent strain. | |||
| EPPL | COMP | Component plastic strains. | ||
| PRIN | Principal plastic strains, strain intensity, and equivalent strain. | |||
| EPCR | COMP | Component creep strains. | ||
| PRIN | Principal creep strains, strain intensity, and equivalent strain. | |||
| EPSW | Swelling strain. | |||
| EPTO | COMP | Component total mechanical strains (EPEL + EPPL + EPCR). | ||
| PRIN | Principal total mechanical strains, strain intensity, and equivalent strain. | |||
| EPTT | COMP | Component total mechanical and thermal and swelling strains (EPEL + EPPL + EPCR + EPTH + EPSW). | ||
| PRIN | Principal total mechanical and thermal and swelling strains, strain intensity, and equivalent strain. | |||
| EPDI | COMP | Component diffusion strains. | ||
| PRIN | Principal diffusion strains, strain intensity, and equivalent strain. | |||
| NL | Nonlinear items (SEPL, SRAT, HPRES, EPEQ, CREQ, PSV, PLWK). | |||
| SEND | ELASTIC | Elastic strain energy density. | ||
| PLASTIC | Plastic strain energy density. | |||
| CREEP | Creep strain energy density. | |||
| DAMAGE | Damage strain energy density. | |||
| VDAM | Viscoelastic dissipation energy density. | |||
| VREG | Visco-regularization strain energy density. | |||
| ENTO | Total strain energy density. | |||
| CDM | DMG | Damage variable. | ||
| LM | Maximum previous strain energy for virgin material. | |||
| FAIL |
Default components: Maximum of all failure criteria defined at current location (MAX), maximum strain (EMAX), maximum stress (SMAX), Tsai-Wu Strength Index (TWSI), inverse of Tsai-Wu Strength Ratio Index (TWSR). Other available components: Other available components: Hashin Fiber Failure (HFIB), Hashin Matrix Failure (HMAT), Puck Fiber Failure (PFIB), Puck Matrix Failure (PMAT), LaRc03 Fiber Failure (L3FB), LaRc03 Matrix Failure (L3MT), LaRc04 Fiber Failure (L4FB), LaRc04 Matrix Failure (L4MT), and any user-defined failure criteria (USR1 through USR9). [5] To activate or remove failure criteria, issue the FCTYP command. | |||
| PFC |
Failure criteria based on the effective stresses in the damaged material. Components: Maximum of all failure criteria defined at current location (MAX), fiber tensile failure (FT), fiber compressive failure (FC), matrix tensile failure (MT), and matrix compressive (MC). | |||
| PDMG |
Progressive damage parameters. Components: Damage status (STAT, 0 = undamaged, 1 = damaged, 2 = complete damage), fiber tensile damage variable (FT), fiber compressive damage variable (FC), matrix tensile damage variable (MT), matrix compressive damage variable (MC), shear damage variable (S), energy dissipated per unit volume (SED), energy per unit volume due to viscous damping (SEDV). | |||
| SVAR | 1, 2, 3, ... N | State variable. | ||
| GKS | COMP | X, XY, XZ component gasket stress. | ||
| GKD | COMP | X, XY, XZ component gasket total closure. | ||
| GKDI | COMP | X, XY, XZ component gasket total inelastic closure. | ||
| GKTH | COMP | X, XY, XZ component thermal closure. | ||
| SS | X, XY, XZ | Interface traction (stress). | ||
| SD | X, XY, XZ | Interface separation. | ||
| CONT | Contact items (STAT[3], PENE, PRES, SFRIC, STOT, SLIDE, GAP, FLUX, CNOS, FPRS). See component descriptions in PLNSOL. | |||
| TG | COMP | Component thermal gradients and vector sum. | ||
| TF | COMP | Component thermal fluxes and vector sum. | ||
| PG | COMP | Component pressure gradients and vector sum. | ||
| EF | COMP | Component electric fields and vector sum. | ||
| D | COMP | Component electric flux densities and vector sum. | ||
| H | COMP | Component magnetic field intensities and vector sum. | ||
| B | COMP | Component magnetic flux densities and vector sum. | ||
| CG | COMP | Component concentration gradient or vector sum. | ||
| DF | COMP | Component diffusion flux density or vector sum. | ||
| FMAG | COMP | Component electromagnetic forces and vector sum. [2] | ||
| JC | COMP | Conduction current density for elements that support conduction current calculation. Components (X, Y, Z) and vector sum (SUM). [2] | ||
| BFE | Body temperatures (calculated from applied temperatures) as used in solution (area and volume elements only). | |||
| CAP | C0,X0,K0,ZONE, DPLS,VPLS | Material cap plasticity model only: Cohesion; hydrostatic compaction yielding stress; I1 at the transition point at which the shear and compaction envelopes intersect; zone = 0: elastic state, zone = 1: compaction zone, zone = 2: shear zone, zone = 3: expansion zone; effective deviatoric plastic strain; volume plastic strain. | ||
| EDPC | CSIG,CSTR | Material EDP creep model only (not including the cap model): Equivalent creep stress; equivalent creep strain. | ||
| ESIG | COMP or blank | Components of Biot’s effective stress. | ||
| PRIN | Principal stresses of Biot’s effective stress. | |||
| INT | Stress intensity of Biot’s effective stress. | |||
| EQV | Equivalent stress of Biot’s effective stress. | |||
| DPAR | TPOR | Total porosity (Gurson material model). | ||
| GPOR | Porosity due to void growth. | |||
| NPOR | Porosity due to void nucleation. | |||
| FFLX | COMP | Fluid flow flux in poromechanics. | ||
| PMSV | COMP | Void volume ratio, pore pressure, degree of saturation, and relative permeability for coupled pore-pressure CPT elements. | ||
| NS | COMP | Nominal strain for hyperelastic material, reported in the current configuration (unaffected by RSYS). | ||
| MPLA | DMAC, DMAX | Microplane damage, macroscopic and maximum values. | ||
For SHELL131 and SHELL132 elements with KEYOPT(3) = 0 or 1, use the labels TBOT, TE2, TE3, . . ., TTOP instead of TEMP.
For the CONT items for elements CONTA171 through CONTA177, the reported data is averaged across the element. To obtain a more meaningful STAT value, use the PRESOL command.
Works only if failure criteria information is provided. (For more information, see the documentation for the FC and TB commands.)
Only valid for SHELL181, SOLID185, SOLID186, SOLID187, SOLSH190, and SHELL281.